1
2
3
4
5
6
7
8
9
10
11
12
13
14
15
16
17
18
19
20
21
22
23
24
25
26
27
28
29
30
31
32
33
34
35
36
37
38
39
40
41
42
43
44
45
46
47
48
49
50
51
52
53
54
55
56
57
58
59
60
61
62
63
64
65
66
67
68
69
70
71
72
73
74
75
76
77
78
79
80
81
82
83
84
85
86
87
88
89
90
91
92
93
94
95
96
97
98
99
100
101
102
103
104
105
106
107
108
109
110
111
112
113
114
115
116
117
118
119
120
121
122
123
124
125
126
127
128
129
130
131
132
133
134
135
136
137
138
139
140
141
142
143
144
145
146
147
148
149
150
151
152
153
154
155
156
157
158
159
160
161
162
163
164
165
166
167
168
169
170
171
172
173
174
175
176
177
178
179
180
181
182
183
184
185
186
187
188
189
190
191
192
193
194
195
196
197
198
199
200
201
202
203
204
205
206
207
208
209
210
211
212
213
214
215
216
217
218
219
220
221
222
223
224
225
226
227
228
229
|
<!DOCTYPE HTML PUBLIC "-//W3C//DTD HTML 4.0//EN">
<html>
<head>
<title>gschem Symbol and PCB Element Transistor Guide</title>
</head>
<body background="./images/paper1.gif">
<center><h2>gschem Symbol and PCB Element Transistor Guide</h2></center>
<hr width=100% size=2>
<blockquote>
The issue is how to manage
a library of gschem transistor symbols and a library of PCB transistor
elements such that we can be confident of correct pin number
correspondence between the libraries. We need to understand
how to handle
the many permutations of emitter, base, and collector (e,b,c)
pinouts and the variations of package number of pins and pin numbering.
This doc shows the approach I've taken in my custom gschem symbols and
PCB elements.
</blockquote>
<h3> gschem symbols </h3>
<blockquote>
There are a couple of ways to consider:
<ol>
<li>Have a base set of gschem transistor symbols such
as npn.sym, pnp.sym, fet.sym, etc which have a fixed and
arbitrarily assigned pin number for the emitter, base, and, collector.
To accomodate the different permutations of (e,b,c) to pin numbers
that exist for transistor packages, you would have to have
a set of PCB elements for each transistor package like TO-92-123,
TO-92-132, TO-92-213, TO-92-231, TO-92-312, TO-92-321, and similarly
for TO-220, TO-5, etc. The problem with this is that manufacturers
do specify pin numbers for their packages and we would be making
many elements with pin numbers not corresponding to real packages.
Remember, a PCB element on a pc board layout is supposed to correspond to
a phycical electronic component.
</li>
<li>Have a base set of gschem transistor symbols which spans the
possible (e,b,c) permutations which can exist for any given transistor
package. The set of gschem symbols for npn transistors would be
npn-ebc.sym, npn-ecb.sym, npn-bec.sym, npn-bce.sym, npn-ceb.sym,
and npn-cbe.sym. There would be similar sets for pnp transistors
and FETs (fet-sdg.sym, fet-sgd.sym, ...). Then there would be
PCB elements only for actual physical transistor packages.
</li>
</ol>
It makes sense to me to say the second approach is obviously better.
Setting up the gschem symbols is simple enough, just create the six
symbols for each transistor type with the pin numbers of the
emitter, base, and collector corresponding to the sequence indicated
in the name. For example, the symbol npn-ebc.sym would have an emitter
<b>pinnumber</b> attribute of <b>1</b>, a base <b>pinnumber</b>
attribute of <b>2</b> and a collector <b>pinnumber</b> attribute of
<b>3</b>.
Now you only need to make
PCB elements with correctly numbered pins for transistor packages as you
need them and you need
to have a systematic approach for naming these elements.
</blockquote>
<h3>PCB Elements</h3>
<blockquote>
A point to keep in mind when looking at transistor package
pin configurations and numbers is that a TO (Transistor
Outline) designation is really only just that - a
designation of a particular shaped and sized outline.
It actually is not a specification of
the pins coming out of that package. Manufacturers may have
have a TO package designation qualified by their internal
"case style" or "package number" code. This qualification determines
the definition of the number of pins, the arrangement of the pins,
and the pin numbering.
<p>
However, most TO packages do conform
to a standard pin numbering convention and have a predominant number
of pins and pin placement configuration.
So it makes
sense to have PCB elements with a particular TO name which can
be used for a majority of cases. Then when a non conforming case
is encountered, we can make a new TO element for it.
<p>
Here's a description of what seems to be the most common transistor
outline configurations:
<ul>
<li> <b>Power Transistors - Plastic:</b>
Look at the package front (where the lettering is) with the pins pointing
down. The pins are numbered left to right (1,2,3). This is very
common, so it makes sense to create initial sets of
three pin PCB elements with this number order using base names
such as TO-126, TO-220, TO-264, etc. For variations such as a five
pin TO-220 package for a LM383, you could make a PCB element with its
name qualified such as TO-220-5, or maybe TO-220-T05B if you wanted
to qualify it with the National Semiconductor T05B package designation
for their 5 pin TO-220 package.
</li>
<li><b>Power Transistors - Metal</b> This would be the TO-3 package which
can have from 2 to many pins. There is no index tab on the package so
you need to look at a diagram of the pin out to see the pin numbering.
The common 2 pin package could be named TO-3, and N pin packages with
N > 2 could be named TO-3-N.
</li>
<li><b>Small Signal Transistors - Metal:</b>
Look at the transistor bottom with the pins pointing at you.
The pins are numbered clockwise from the index tab (1,2,3,...)
Metal can packages such as TO-18, TO-39, or TO-72 will frequently
have 3 or 4 pins, while the TO-5 may have 3, 4, 5, 6, 8, or 10 pins.
Because of the variable pin numbers, you could, for example, name the PCB
elements TO-18-3 and TO-18-4, or you could use TO-18 and TO-18-4
assuming that a three pin can is more common and thus earns the
base TO-18 element name.
</li>
<li><b>Small Signal Transistors - Plastic:</b>
Look at the transistor package flat side (where the lettering is)
with the pins pointing down. Almost all packages where the three pins
are in a straight line will have the left to right pin number ordering
of (1,2,3) and these can be the base TO-92 PCB element.
There are a very small number of cases where the pins will be in a
straight line and numbered left to right (3,2,1). You could have a
distinct PCB element for these, but you could also decide to ignore
the manufacturer's pin numbering and pretend it's the more common
(1,2,3). However, if the package has the middle pin
offset so the pins are in a triangular arrangement, the pin number
ordering will frequently be (3,2,1) and this will possibly require a
custom PCB element. But see my comments about my <b>TO-92o</b>
element below.
</li>
<li><b>Surface Mount Transistors:</b> The SOT (Small Outline
Transistor) packages are much more standard than the TO packages
and the pins are consistently numbered counterclockwise from the
top left as are IC packages. But for a transistor that has a
TO and a SOT version, you can't simply change the
<b>footprint</b> attribute on the schematic because the package
pin numbers don't map the same to the emitter, base, and collector.
You need a separate gschem symbol for them. For example:
<b>2N3904.sym</b> for the TO and <b>MMBT3904</b> for the SOT.
</li>
</ul>
<h3>General Procedure</h3>
<blockquote>
The process of using a transistor for the first time in a gschem
to PCB design takes these steps (2N3904 used as an example):
<ol>
<li>Most transistor spec sheets can be found in pdf format on
the web, so get one and determine the case style and pin
name and number ordering. For the
2N3904 the case style is TO-92,
the pin number order left to right is (1,2,3),
and the pin name order left to right is (e,b,c).
</li>
<li>If we have a PCB element in our library for that case style
with the correct pin number order, use it. If not, make a
new PCB element. For the 2N3904, I have a <b>TO-92</b>
element in my custom library that has the pin number order
of (1,2,3), so I can use it.
<li>Copy the gschem transistor symbol corresponding to the pin name
order to a new transistor symbol name. For the 2N3904 example,
the pin name order is (e,b,c) so copy the base symbol
npn-ebc.sym into 2N3904.sym.
</li>
<li>Edit the new symbol and change the <b>value</b> attribute to
the transistor name and the <b>footprint</b> attribute to
the right PCB element. For our example, this would be
<b>2N3904</b> and <b>TO-92</b>
</li>
</ol>
</blockquote>
<h3>Special Cases</h3>
<ol>
<li>I have in my library a <b>TO-92o</b> PCB element which has the middle
pin offset so the pins are in a triangular arrangement. This element
has the left to right pin number order of (1,2,3) and can be used
in place of the <b>TO-92</b> for layout considerations. You only have
to slightly bend the middle pin of the transistor when installing it.
</li>
<li>The BC546 transistor spec sheet shows its pin number order to be
(1,2,3) in a straight line and the pin name order to be (c,b,e). But
I've seen this transistor shipped from the factory with the middle
pin pre-bent into the offset configuration. For this transistor,
you would create the gschem symbol from npn-cbe.sym as expected
but use the PCB element TO-92o.
</li>
<li>The BF240 transistor spec sheet shows its pin number order to be
left to right (3,2,1) in a straight line and the pin name order would
be left to right (c,e,b). If you made a new PCB element with
pins numbered (3,2,1), then you would have to create the gschem
BF240.sym from npn-bec.sym because pin 1 on the PCB element has
to correspond to pin 1 on the gschem symbol. But it would be
easier to just ignore this uncommon pin numbering and assume
the transistor pins are actually numbered the standard left to right
(1,2,3).
Then you could use the existing TO-92 PCB element and create the
gschem symbol using npn-ceb.sym. Some transistor spec sheets give
the pin name order and do not give a pin number order, and for
these you just make the same assumption that the pins are numbered
left to right (1,2,3).
</li>
<li> In the second case above, the transistor had an offset pin 2
when the spec sheet showed the pins in a straight line,
and the pin numbers on the spec sheet were ordered left to right
(1,2,3). But many transistors have the offset pin 2 indicated on the
the spec sheet and the pin numbers are ordered left to right (3,2,1).
You could use an element such as my TO-92o by ignoring the spec
sheet ordering as I suggested in case 3. But this configuration
is much more common than the BF240 example so you might want to
have a distinct PCB element for it with pins numbered to match
the spec sheet.
</li>
</ol>
<p>
<hr>
<address>
<p align=center>
<a href="http://web.wt.net/~billw/gsch2pcb/tutorial.html"
name="www.gkrellm.net">Back to gsch2pcb Tutorial</a>
<br>
Bill Wilson <A HREF="mailto:bill--at--gkrellm.net">bill--at--gkrellm.net</A>
<br>
</p>
</address>
</body>
</html>
|
